LTspice Lesson 3: Transmission lines part 1

Kashif Javaid

In this lesson we will focus on single element Lossless Transmission line (T-line) as shown in Figure 1. Lossless T line simulation will be introduced here. One of the goal of these lessons are to give out practical examples from real world. Transmission line model real world signals very well. This lesson focus on the Lossless T-line where no power gets dissipated during transmission. In a future lesson, we will focus on lossy line and loss mechanics.

Screen Shot 2019-08-26 at 8.36.03 PM

Figure 1: LTspice symbol

What is transmission line? A transmission line is any conductor along with a return path where a signal travel from source to load. Because of finite speed of light, a signal takes a finite amount of time called Time Delay (TD) to go from source to load. Signal sees a characteristic impedance (Zo) based on geometry and dielectric around the conductor and return path. For an in-depth review of transmission line, please refer some excellent references as given at the end.

In any simulation we need to build confidence on the models given. One way to do this is find solution of easy problems by hand for cases a formula or numerical values can be derived and then compare them with results from simulation. Once 100% agreement is established, one can go beyond simple situation and start modeling real world effects. In the case of transmission line, let’s look at 4 simple but common cases, where a 50Ω T-line is driven by a CMOS driver with 5Ω source impedance (typical for newer drivers) with an open load, short load, 100Ω load and a properly terminated 50Ω load. 

For each case, we will look at the load voltage waveform using bounce diagram. If you haven’t learned or played with bounce diagrams, do not fret, we will walk through it step by step.

First case: Load = Open or Hi-Z

For an open load situation, let’s start to build a bounce or reflection diagram for the below open circuit:

Screen Shot 2019-08-26 at 8.42.32 PM.png

Figure 2: CMOS driver with low impedance driving 50Ω line with no load.

Observations:

  1. In any circuit, there is signal path and return path which is as important as signal path.
  2. After the long time meaning several transit time (TD) has been passed, T-line has becomes ideal and since load is open or Hi-Z, voltage at VL will approach 3.3V, after all it’s an open and no current can flow.
  3. Getting to final 3.3V would take several TD (illustrated below by creating bounce diagram step by step section and LTspice simulation).
  4. Reflection coefficients at load and source are calculated in Figure 3.
  5. Reflection coefficient is 1 for an open load case. A

Screen Shot 2019-08-29 at 8.54.09 AM.pngFigure 3: Formula and calculation of Reflection at source and load.

Building Bounce Diagram one TD a time:

Bounce or reflection diagram consist of two axises. Horizontal axis represent location on transmission line and goes from z=0 to z=d where d is actual length of transmission line. Vertical lines represent time and marked as in unit of time delay (TD).  We draw a first line representing the signal launched into transmission line. Note V+  and I+ represent the initial waveform voltage and current signal. These signals encounter the impedance of the line, in this case 50Ω. V+ is calculated using the voltage divider formula as 3.3V(50Ω/(50Ω+5Ω)) = 3V and I as  V+/Zo. 

Similarly V and I show reflected voltage and current waveforms respectively. These are calculated using Load reflection coefficient. Similarly V++ and I++ are calculated using generator reflection coefficient and represent reflected waveforms from source after 2 TD. The “tennis match” continues as illustrated in the series of diagrams below:

Screen Shot 2019-08-26 at 8.55.27 PM.png

Screen Shot 2019-08-26 at 9.15.45 PM.png

Screen Shot 2019-08-26 at 9.21.38 PM.png

Screen Shot 2019-08-26 at 9.22.22 PM.png

Screen Shot 2019-08-26 at 9.23.07 PM.png

Screen Shot 2019-08-26 at 9.24.19 PM.png

Figure 4: Building up the bounce diagram

I intentionally picked this example as source and load side impedances are severely mismatched. In-fact load is open with infinite resistance. I think we have enough data to make comparison with LTspice. Here is the load voltage waveform by hand if you were to put an oscilloscope at the load side, this is what we will measured. Of-course, this is not complete as final value should be 3.3V, but it will take several more bounces before it reaches this value, but we let LTspice handle it.

Screen Shot 2019-08-26 at 9.29.59 PM.png

Screen Shot 2019-08-26 at 9.31.07 PM.pngScreen Shot 2019-08-26 at 9.31.34 PM.png

Screen Shot 2019-08-26 at 9.38.28 PM.png

Screen Shot 2019-08-26 at 9.38.52 PM.pngScreen Shot 2019-08-26 at 9.39.10 PM.png

Figure 5: Building up the load voltage waveform

Here are LTspice results:

Screen Shot 2019-08-27 at 11.15.56 AM.pngScreen Shot 2019-08-27 at 11.18.21 AM.png

Figure 6: LTspice simulation for open load transmission line

As marked on the waveform, first 6 Time Delay (TD) values are agreed 100% to our calculated values. But notice that it takes several bounces back and forth actually more than 50ns before a steady state value of 3.3V reached. First time I learned this it was really surprising, but it is a direct consequence of finite speed of light and mismatch between source and load impedance.

Second case: Load=0Ω or short

Second interesting case is when load is shorted after the transmission. Since load is shorted, output voltage should be zero, but it will be current that will build up to its final value according to ohm law, I = 3.3V/5 = 0.66A.

Screen Shot 2019-08-30 at 11.40.27 AM

Figure 7: Transmission line for shorted output,  note very small value of resistance is used for probing otherwise LTspice won’t give us the current waveform at the load.

Let’s calculate first few TD using the bounce diagram and then we let LTspice calculate the rest of it.

Screen Shot 2019-08-30 at 11.51.50 AM.png

Screen Shot 2019-08-30 at 11.52.53 AM.png

Figure 8: Bounce diagram and current waveform. y-axis is current in Amp and x-axis is time in unit of TD. 

Here are LTspice results. Note the agreement between calculated and simulation values. One thing to note is that since we used a very small resistance (just think of resistance of the wire) at the output, voltage will be also climb up like this which you can easily verify it using the attached simulation files.

Screen Shot 2019-08-30 at 12.00.26 PM.png

Figure 9: Simulation results of shorted load

Third case: Load=100Ω

This is a typical case where where T-line is driving 50 ohm line with load impedance of 100ohm. Screen Shot 2019-08-30 at 11.44.30 AM.png

Figure 9: 50Ω Transmission line driving a 100Ω load

Here is the bounce diagram and LTspice simulation results for this case:

Screen Shot 2019-08-30 at 12.09.33 PM.png

Screen Shot 2019-08-30 at 11.44.16 AM.png

Figure 10: 50Ω Transmission line driving a 100Ω load and its bounce diagram and LTspice simulation results

Fourth case: Load=50Ω

If load is matched with characteristic impedance there will be no reflection and perfect matching will occur. In-fact this is one of a termination scheme in the high speed digital logic circuits. Bounce diagram is very boring, but it show after 1 time delay of latency signal will reach its equivalent value of 3.3*(50/55)=3V. Notice this 50Ω termination has reduce the output voltage by 300mV and will eat up the noise margin. Also, high power consumption is the second factor with this scheme. That’s why other termination schemes are typically employed but this topic warrant its own post.

Screen Shot 2019-08-30 at 11.46.36 AM.png

Figure 10: 50Ω Transmission line driving a 50Ω matching load

Here is the bounce diagram:

Screen Shot 2019-08-30 at 12.22.34 PM.png

Screen Shot 2019-08-30 at 11.46.44 AM.png

Figure 10: 50Ω Transmission line driving a 50Ω matching load, output voltage, after 1ns of TD, reaches is final value of 3V.

In essence, learning any simulation tool is basically checking fundamental equations and methods against it. Only then one can advance to more complicated and real-world modeling. Hope this post not only show how to simulate transmission line but gives out a good refresher on bounce diagram. Please feel free to post any comments, I will continue to improve on these lessons. Next lesson: Generate Electronic Sources.

Download LTspice file: Tline_3_cases.asc

References:

Gregory D. Durgin, Andrew F. Peterson, Transient Signals on Transmission Lines: An Introduction to Non-Ideal Effects and Signal Integrity Issues in Electrical Systems, ISBN-10: 1598298259

Bogatin, Eric Signal and Power Integrity – Simplified (3rd Edition), ISBN-10: 013451341X

If you want to discuss it then jump here:

https://www.eevblog.com/forum/projects/ltspice-lesson-3-transmission-lines-part-1/new/#new

Advertisements

About iexploresiliconvalley

My name is Kashif. I live in the heart of silicon valley and have been living here for a very long time. My passion is engineering, technology and traveling. My email is kashifjavaid@hotmail.com. Please feel free to contact if you have any suggestion or comments on any of my posts.
This entry was posted in LTspice for EE students. Bookmark the permalink.

Leave a Reply

Fill in your details below or click an icon to log in:

WordPress.com Logo

You are commenting using your WordPress.com account. Log Out /  Change )

Google photo

You are commenting using your Google account. Log Out /  Change )

Twitter picture

You are commenting using your Twitter account. Log Out /  Change )

Facebook photo

You are commenting using your Facebook account. Log Out /  Change )

Connecting to %s